Mechanical APDL Basic Analysis Guide - Ansys

Command
GUI Menu Paths
Main Menu> Solution> Load Step Opts> Sol'n Control
( : Basic Tab)
Main Menu> Solution> Load Step Opts> Output
Ctrls> DB/Results File
Main Menu> Solution> Load Step Opts> Output
Ctrls> DB/Results File
Purpose
and results file and how
often it is written.
OUTPR Main Menu> Preprocessor> Loads> Load Step Opts> Controls what is printed
Output Ctrls> Solu Printout
(written to the solution
Main Menu> Solution> Load Step Opts> Output output file, Job-
Ctrls> Solu Printout name.OUT) and how of-
Main Menu> Solution> Load Step Opts> Output
Ctrls> Solu Printout
ten it is written.
The example below illustrates using OUTRES and OUTPR:
OUTRES,ALL,5 ! Writes all data every 5th substep
OUTPR,NSOL,LAST ! Prints nodal solution for last substep only
You can issue a series of OUTPR and OUTRES commands (up to 50 of them combined) to meticulously
control the solution output, but be aware that the order in which they are issued is important. For example,
the commands shown below will write all data to the database and results file every 10th substep and
nodal solution data every fifth substep.
OUTRES,ALL,10
OUTRES,NSOL,5
However, if you reverse the order of the commands (as shown below), the second command essentially
overrides the first, resulting in all data being written every 10th substep and nothing every 5th substep.
OUTRES,NSOL,5
OUTRES,ALL,10
As another example,
OUTRES,NSOL,10
OUTRES,NSOL,ALL,TIP
writes the solution at all DOFs every 10th substep and the solution at the node component "TIP" every
substep. Again, if you reverse these you will only obtain output at all DOF every 10th substep.
Note
The program default for writing out solution data for all elements depends on analysis type; see
the description of OUTRES in the Command Reference. To restrict the solution data that is written
out, use OUTRES to selectively suppress (FREQ = NONE) the writing of solution data, or first
suppress the writing of all solution data (OUTRES,ALL,NONE) and then selectively turn on the
writing of solution data with subsequent OUTRES commands.
A third output control command, ERESX, allows you to review element integration point values in the
postprocessor.
Command(s): ERESX
GUI: Main Menu> Preprocessor> Loads> Load Step Opts> Output Ctrls> Integration Pt
Main Menu> Solution> Load Step Opts> Output Ctrls> Integration Pt
Main Menu> Solution> Load Step Opts> Output Ctrls> Integration Pt
Release 13.0 - © SAS IP, Inc. All rights reserved. - Contains proprietary and confidential information
of ANSYS, Inc. and its subsidiaries and affiliates.
2.6.4. Setting Output Controls
61